Is it possible, if so how, to configure the occurrences to be omitted in a pattern (moreover, a pattern-driven pattern of components)?
Hello
"Configure" i.e. choose the repetitions to be used according to the configuration?
If you change in one configuration and it changes in all of them, then it must not be possible!
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Hello, why do you need to do this?
Maybe we can find an alternative?
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There is a request for improvement on this subject on the SolidWorks website, so it is not possible:
SPR #:530195
Product:SolidWorks
Status:Open
Fixed in:none none
Area:Parts
Sub-Area:Configurations - Parts, General
Customer Impact:High
Enhancement:Yes
Summary:Ability to have configuration specific Instances to skip for Pattern command
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No, that's not possible!
Even less a repetition driven by a rehearsal!
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So the only solution I see is to do several repetitions, and to delete the one where there are the instances to be omitted in the appropriate configuration...
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Afterwards, if it's to settle the number of occurrences, we can go through an equation...
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One way out is to directly delete (disable/grey) the occurrences in the list of components of the repeat function and according to the configurations.
But not directly by editing the function.
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It was .PL that, unfortunately, responded well.
@Benoit, that's how I do it but it's still not very practical when there are "many" parts (see below).
@Bart, to situate the problem: I integrate equipment that is limited on trays. The table top is common but it can accommodate from 1 to 4 identical materials, so each material has its flange and the associated screws. The goal was to easily make 5 configs.
Sorry for the image quality...
presse-papiers-1.jpg
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Ok, basically we had to remove the occurrences of oblongs that were under the cases.
Depending on the position of the housings, the oblongs had to match.
In this case, I would use a boss that I would dimension according to the cases that would fill the holes under the cases.
See image.
occ.png
So in this case, there is a faster and more flexible way.
In the assembly that contains the perforated plate, insert the component to be repeated. Create a drilling function (like making a Ø8.5 hole if the grooves are 8 wide so that it is discreet) at the assembly level and place the holes at the level of the first component and in the places where you want to find the following occurrences. Finally, insert a feature-driven pattern using the drill function.
So to move, delete or add components you just have to edit the drilling sketch.
It would be even easier if "sketch-driven repetition" were accessible at the assembly level and not just at the part level!!
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You said out loud what I thought in a whisper =)
I often have to deal with occurrences and I always go through bosses that I force.
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@ Bart, not quite, it's not the oblongs that need to be configured but the cases, which are constrained in relation to the holes in the platter (the image I gave corresponds to the configuration with 4 cases).
The goal is not to add functions.
Hello
Sketch-driven component repeats have been around since SW2014.
See image.
@+
pilote_par_esquisse.png
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