Stamping

3D Design Volume Model
1

Hello, are there any detailed tutorials that show how to design a LAY-OUT (progressive die)

Thanks in advance 

 

2

See this page Un max de tuto catia progressive die you tube

https://www.youtube.com/results?search_query=catia+progressive+die

good reading

@+

 

3 Likes
3

there is nothing special that could help me in this link, in fact what I want is to design the tape (tool to follow) and this is done in the generetive sheet metal design workshop and I have no idea about this workshop 

1 Like
4

If you want answers to your questions try to define your request

otherwise you will always have answers about or before

so explain what you want to do

So for generative sheet metal

https://www.youtube.com/results?search_query=catia+v5+generative+sheet+metal+design+

Show us a picture of what you want not to forget a picture worth a thousand words

You can insert images via the postcard in the answer bar

@+

1 Like
5

BAh I want to design parts as in pictures and I'm looking for a detailed tutorial


bande.png
6

That's exactly what you were presented on the tutorials

you have a sheet metal plate

it must be

 Cut, drilled and bent and rediscovered

We must try to see the step and the stages of transformation of this said sheet metal

you won't find a ready-made tutorial

The first you tutorial shows you a tool with 2 punches and your piece moves forward step by step

So it's up to you to define the steps and the tools you need to create your said part

@+

3 Likes
7

Hello

I join Gt22

The SDM (generative sheet metal design) workshop is a sheet metal workshop (bent parts).

It can be used to create the final (folded) and (unfolded) part.

But for the stripping and the tools to follow,  Dassault Systèmes has a business offer (methodologies, workshop, libraries, developments, training).

It is unlikely that these elements will be freely found on the internet.

There are dedicated business software (Logopress  for example)

Of course, you can design the striping under SMD but without this offer or methodology, the slightest change on the final  part (by the design office produced) may have a big impact on the update load of the stripping.

Just with SMD

 

 I would say that first I would draw the final piece.

Keeping in mind the order of operations carried out by the tool to be followed.

After that, I would try to keep as much as possible the associativity with the final piece.

I would use the special gluing function, then translation (not of the tool) – unfolding, and so on, last I remove the cuts and stampings (Part design function, face removal, or others).

One should get the parts at each step in advance of the tool to follow.

In the example, the modification of the rectangular cut followed

All that remains is to copy this result with a link in another CATPart where we will build the side of the tape.

1 Like
8

Here's what it can look like on your example:

I'm not saying it's the "METHOD" (it's not my job)

But on this type of piece

This should be robust enough to keep up with small BE tune-ups on the final part

1 Like
9

Thank you both; Your suggestions helped me a lot 

10

And how did you manage to cover the pieces with the side? 

11

Hello.

they are not parts, they are not an assembly (CATProduct).

Only the screenshot on the left is the Sheetmetal part.

The middle capture is an assembly of parts in a room (CATPart).

The bottom 5 bodies are a special copy/paste, (with link and views).

Then I do a translation of the pitch of the second copied body.

Then a translation of 2 x the pitch of the third body copy.

And so on until the fifth.

On the fifth I do the unfolding.

Then I copy /paste special, (with link and views) this fifth body (5x).

I copy/paste each successive translations made on the previous Corps (parts still folded).

Then on the last body (the top +) I delete the cutouts.

I assemble all these bodies to the main body.

I copy/paste this main body (as a result with link) into a new CATpart.

In a sketch (drawn in white) in the third screenshot I fill in the gaps (cut-outs of the flank) and then I extrude this sketch to the plane (material thickness)

I then go over the rays and the symmetry.

Note the steps of copying and pasting with links between two operations could be automated by Macro.

As I said, I don't have the hindsight to say that this is THE METHOD!!

But it seems to me flexible and robust enough to withstand the modifications, fine-tuning of the parts and the tooling.

Below is a modification of the oblong and the addition of two holes less than three minutes.

 

12

C well I solved the problem .. Thank you Bcp