Otherwise, don't make a body repetition, but a function repetition (extrusion delimited by a surface) no need to go through a sketch.
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The problem is that my part is built with mechanically welded elements. If I make a sketch that I extrude, I no longer use my database with all my profiles and the table of welded elements will not be compliant (at least I think...)
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And this component, could you extend it?
Yes, I can extend it (currently the slat is extended in the lower part and adjusted in the upper part).
In my attachment at the beginning I used the Adjust/Extend function by selecting all the slats one by one.
And make a sketch of the section to be extended on the middle plane (projection of the contour), extrude to a surface in both directions and merge with the part, then repeat this extrusion.
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This method seems to work at first glance. Thank you
I still have to find how to retrieve the characteristics of my basic profiles (description, ...) so that the welded parts table is up to date automatically.
I'm going to dig a little deeper.
um I don't think I can retrieve the custom properties with this method, the extrusion function is based on a sketch that can't have a feature.
If I use this method, I'm going to have to manually change the properties of the welded parts with each change.
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I noticed something that may help you, if you move the bodies of the repeat to the original part folder, and you vary the number of repeats between 2 and the number of bodies you moved in the folder, they will stay in that folder. Anyway, look attached...
2017-02-14_at_17-21-32.mp4
Hello
I give a method already given, repeat your bodies without limitations and do a removal of materials (interior sketch of the frame) afterwards.
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mecano_soude.png
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@christophe_4
Have you looked at the tutorials posted
There's everything you want in it
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Coyote would be too simple, it's sure that delimiting bodies with a surface would be ideal. But each body added by this repetition will not be taken into account, otherwise it would have to apply to all bodies including the crossbar of the frame. If you put your sketch inside the frame, do you create a game to separate the bodies?
@a.leblanc, that's why I make the bars before the frame, look at my image!:
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Good evening
Coyote gave you the best way to do things for me (and the only one I know of to date).
The problem comes from the fact that on SW, we cannot automatically select the bodies created by a function (in other words, to do for example a repetition of bodies by selecting the parent function of this field).
The idea is therefore to:
- Create your frame structure in a sketch
- Create a second sketch for a rung, making sure it protrudes enough from the frame
- Putting a profile on the bar
- Doing the linear repetition
- Create a third sketch consisting of only one line (spline, arc, but no closed outline)
- Doing the extrusion remember to check the box "All bodies" in the group "Area of assignment of the function"
- Put profiles on the portal frame
For the symmetry of all this, no luck, it's not possible.
2 solutions:
- Draw everything in duplicate in the sketches (dynamic symmetry to go faster) and follow the same approach as for a leaf.
- Create an assembly and symmetrize the part. (Be careful in the MEP, the quantities are for a single leaf)
Personally, I prefer the first solution for a gate or railings.
Kind regards.
portal.sldprt
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Indeed, I agree with Coyote, we should make the bars before the frame, and use plans or sketches to delimit them, that would be the simplest. On the other hand, I don't see why a symmetry of the bodies can't be achieved afterwards according to a median plane.
Hello
@A.Leblanc: I may have gone a little too fast in saying that for symmetry, it's not possible.
It can be fed, by code or manually each time the number of rungs is changed.
As I said in my previous post, SW does not allow you to select, for a repetition of fields (or symmetry), the parent function of the fields. Therefore, how to select the bars that are not created since to make the symmetry (of the body), you have to select the bodies one by one?
If we want to make a complete symmetry, we have no choice, it's either by a macro that will recover the bodies for us or by drawing the whole.
Kind regards.
Why not a symmetry of function, have you seen the video above, the bodies can be moved in the same folder as the original part, which can be used to have a correct nomenclature
On the other hand, since these are imported fields, it is not possible to go through a symmetry of function. The simplest way would be to drive a repetition of bodies for the 2nd leaf according to that of the 1st leaf (with some relations such as number of bodies repetition 2 = number of bodies repetition 1).
Hello
Thank you for all your answers and your food for thought.
I started with the industrialcadservices solution : I first create the bars and then I delimit them by removing material and only then do I come to do the outside of the frame.
By this method the gate is manufactured automatically without touching anything and I keep my personalized properties of my welded construction profiles!! =D
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Uh..... it's not my solution sometimes ;)....
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Hello
Indeed, it was Coyote who gave you the answer, I may have only illustrated it a little better :)
In any case, glad we were able to help you.
Kind regards.
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