Hello
In solidworks, how to easily make a partial chamfer on an edge by defining the tool radii at the ends?
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Hello
I don't know Solidworks because I work with Inventor.
But I often have to make partial chamfers on pieces of wood.
To do this, I create a construction plan passing through the chamfered edge, then on this plan I draw a path and at the start of this path I draw an element to be extruded and which will follow this path.
I make wooden posts with edged chamfers.
I hope I have helped you.
Kind regards
Hello
It is possible to split the part, bevel it and then recombine it. It is true that this is not easily done but it is practical for some cases (see the png attached).
Have a nice day
sans_titre.png
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I tried with a dividing line, it doesn't work...
So Matthieu's solution, it's rather fast so that's :).
chanfrein_essai.sldprt
you draw your straight stripe sketch on an offset axis
and removal of material in the right of your chamfers on which you indicate a 45° angle
@+ ;)
The best thing to do is to remove the swept material.
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yes also an elevation of swept matter
but in this case at each chamfer a function of elevation of the swept material
In my option you can make x chamfer on the same side simple and quick
@+
Even simpler, you have to remove material with a slim function and a 45° draft. With a line and leave, you have the desired result.
capture.jpg
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I like Matthew's method, but the rounded ends still need to be done.
As for the swept removal fct, I don't really see what the sketches could look like.
The guide curve option is I think + heavy than
The material removal option via the straight striped sketch with 45° inner draft
All you have to do is shift the axis of this sketch of (or these) stripes and dimension this (or these) lengths
but that's just my opinion
The leave can be modified as desired
Possibility of placing all the fillets of one side on a single plane
example:
http://imageshack.com/scaled/medium/197/ppty.png
@+ ;)
2 Likes
Hello
Indeed, it is necessary to use a Sweeping function by removing material. The advantage is that the shape of the section can be straight, domed or any. Moreover, it can be a library function... well, only advantages!
Kind regards
chanfrein.png
4 Likes
I like the idea of GT22,
a groove sketch and extrusion with a 45° draft.
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Hello
The problem is that you're going to have chamfers with 90° inlets and outlets.
Whereas pbois wants an inlet and outlet of its chamfers with a radius (corresponding to a tool radius).
And after sweeping the first bevel, you make a circular network (from 4 to 360° to bevel 4 edges).
Kind regards
ia001800_vue2.jpg