Switching from Pro Engineer (Creo) to Solidworks, we encounter a major problem when developing our drawings:
As you can see in the photo from Creo, when creating cylindrical parts, we could display a double arrow that allows us to mention the dimension by diameter without necessarily displaying the whole part.
The length of this double-arrow rib was of our own free will, we didn't have to make it go to the edge of detail like on Solidworks.... A solution?
Indeed, it turns out that on Solidworks, when we make a detail of a cylindrical part, the dimensions with the double absolutely stick to the edge of our detail. We can neither make them go further, nor bring them closer....
Consequence = if the detail is complex, we are quickly overloaded.
Another example see PJ: We want to cut a crown and display only one half on an A4 Vertical plane (otherwise it makes the machining of the crown too small and illegible). We have the possibility to do it via detailing, trimming, local cutting.
Whatever we choose, we manage to make the half view appear , but the dimensions remain displayed at the diameter.
We could "cheat" by making a mega hidden detail as explained above to be able to get the ribs with the double arrow but, same problem, they will go to the end of the detail obligatorily, something we don't want.
See attached what we were doing with Pro Engineer, and what we couldn't do with Solidworks.
So it's quite peculiar, but you first have to create the dimension in a front view of the diameter and then transfer it to the cropped view (ctrl + dimension hung with the mouse).
By having set the reduced dimensions on the double arrow, we obtain the same result as on creo.
I couldn't find an option to change a dimension to "reduced" on a cropped view. The option is only available when injected from another view.
you can also create the dimension directly in the cropped view, by selecting a circular edge, the dimension will land but without a reminder line on the side outside the view, by selecting the dimension, a square is displayed at the end of the arrow in the void, by clicking-left-held you can move it, and bring it back where we want.
I don't know if it's coming from my pc (I don't have time to go into depth, SW2017-SP-5.0), but the double arrow with the zigzag to signify the cropped part of the dimension doesn't care, it remains the basic arrow...
Important reminder: yes the act of setting a dimension by selecting that an entity may be a problem later, if you add a fillet or chamfer.
