Hello
If it's really urgent, there's always the possibility of tinkering with it!
Effect the crenellated fillet and redraw a nice arc over it .
Neither seen nor known!
Fred.
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Hello
By reducing the deviation or checking the box, improving the quality of the curve doesn't change anything? And the view is in high quality?
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Hi @ Benoit
and if you put your wired resolution to the max
and your deviation to the minimum
and improve the quality of the curve by applying a higher level
this is the typical problem that we find under SW for watchmaking
after tests we say
Thank you
@+ ...........................
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Tests done with the following parameters (see image) on the slddrw. It doesn't change anything! :/
The "High Quality" is only accessible for thread representations (I'm on SW13) and is enabled.
Edit: If watchmakers work with the same parameters as me, making slots on 10mm radii, we're in a bad ;D
screenshot426.jpg
Have you tried to make an impression with diff parameters?
@+.................
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You can try the following at home:
_dans a sldprt, 2 lines then 10mm fillet at their intersection
Chain _Sélection, Tools/Spline Tools/Adjust Spline, value 0.1mm
_Insertion/Surface/Extrusion on x mm
Room _Enregistrement and 1:1 scale drawing
What does it look like?
And when exporting to PDF or DWG, do you have the same problem?
Does your customer only want a SolidWorks plan?
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@gt22, I printed it out and it looks like on the screen. Even sharper!
This plan is intended to be printed (paper or pdf) for commercial purposes, to explain a delicate technical point (we are in pre-sales). I need something convincing (commercial) and sustainable (risk of having to modify it on the fly).
If I don't get my way, I'll use @Frédéric's proposal, but it's not the best, we agree.
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Hello
I did what you say: 2 strokes then leave, then....
At home, everything stays clean, even in the drawing!
I'm in 2014, is that the cause????
@+
Edit: can you do the indicated test and ask us on the post.
I just tried it and I don't have the problem (it's facetized, but not as much)
What is the largest size on your part? (wouldn't SW limit the facetization to avoid calculating on large dimensions)
Why use a spline? Select Chain/ Insertion/Surface/Extrusion on x mm works directly
(or I missed something)
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With the fillet tool you have a better deflection resolution
I go to 0.04604 and I'm not in the red
The image resolution at the max
and the level of detail at most
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Well, I'm losing my Latin: I redid the test I proposed to you and it doesn't facetize.
But for my example at the beginning, it's always the same! :/ Note that when I remove the spline to extrude the base segments it doesn't look facetized anymore!. But I really need the spline for my movements (unless I use a method like the one proposed by @frédéric, but I like to understand what's going on for the next time!)!
I enclose the play and its drawing.
@Pascal, you didn't miss anything, I come to make a surface on a spline to be able to place a constraint between a point of a subset on this surface. It's for a cutscene.
blf_epure.zip
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Hello
A weird solution but it works on your file, switch the view to shaded more edge...
See attached image!
ombre_plus_arete.jpg
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Indeed @coyote!
The problem is that on a drawing of an assembly containing this part, I have to switch the whole view to Ombre! I can't just pass the part that causes me problems. And that bothers me (yes I know, never happy!).
But the lead is interesting! There must be a subtlety that escapes us!
Hello
It looks like a bug, it's reported on the knowledge base and this one is not fixed (Open status)
"File specific: fillet causes extra lines to display in high quality, hidden lines removed/visible (HLR/HLV) drawing view of part"
https://customerportal.solidworks.com/eservice_enu/start.swe?SWECmd=InvokeMethod&SWEMethod=GotoRecord&SWEService=SWGotoRecord&ViewName=SW+All+Defects+List+customerportal+-+Search&BusObject=Product+Defect&BusComp=Product+Defect&Id=1-199L2CT&SRN=
There are others by searching for "fillet drawing display".
Hello
Another solution is to convert the view to a sketch (if you're in 2014)!
@+
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@coyote
I'm under 2013. Lost ;)
What escapes me is that it's not repeatable.
This is clearly stated in the SolidWorks bug:
"File specific: fillet causes extra lines to display in high quality, hidden lines removed/visible (HLR/HLV) drawing view of part"
"Specific to certain files: a fillet displays additional lines in high quality, hidden lines visible or removed on the part drawing".
No solution at the moment.
@Lucas,
Except that in this case it's not really a fillet anymore, since the (sketch) fillet only serves me as a support to adjust a spline which itself is reused for a surface extrusion function.
The SW bug doesn't give more details than what you give? More detailed circumstances of the bug in particular?