Aliasing a curve on a drawing

3D Design Volume Model
1

I have a drawing that shows an extruded surface whose sketch is a spline fitted on 2 lines connected by a 10mm fillet.

 

My problem is that on my drawing, the 10mm radius appears fragmented into 2 segments (not acceptable to leave it like that, plan for a client). I can't figure out where the problem comes from, on 3D, it's almost not crenellated.

 

Attached is a view of the drawing and the configuration of the slddrw and below the 3d (sldprt) and its configuration.

 

Thanks in advance


screenshot428.jpg
2

Hello

 

If it's really urgent, there's always the possibility of tinkering with it!

Effect the crenellated fillet and redraw a nice arc over it .

Neither seen nor known!

 

Fred.

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3
Hello By reducing the deviation or checking the box, improving the quality of the curve doesn't change anything? And the view is in high quality?
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4

Hi @ Benoit 

and if you put your wired resolution to the max

and your deviation to the minimum

and improve the quality of the curve by applying a higher level

this is the typical problem that we find under SW for watchmaking

 

after tests we say

Thank you 

@+ ...........................

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5

Tests done with the following parameters (see image) on the slddrw. It doesn't change anything! :/

 

The "High Quality" is only accessible for thread representations (I'm on SW13) and is enabled.

 

Edit: If watchmakers work with the same parameters as me, making slots on 10mm radii, we're in a bad ;D


screenshot426.jpg
6

Have you tried to make an impression with diff parameters?

@+.................

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7

You can try the following at home:

_dans a sldprt, 2 lines then 10mm fillet at their intersection

Chain _Sélection, Tools/Spline Tools/Adjust Spline, value 0.1mm

_Insertion/Surface/Extrusion on x mm

Room _Enregistrement and 1:1 scale drawing

 

What does it look like?

8

And when exporting to PDF or DWG, do you have the same problem?

Does your customer only want a SolidWorks plan?

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9

@gt22, I printed it out and it looks like on the screen. Even sharper!

10

This plan is intended to be printed (paper or pdf) for commercial purposes, to explain a delicate technical point (we are in pre-sales). I need something convincing (commercial) and sustainable (risk of having to modify it on the fly).

 

If I don't get my way, I'll use @Frédéric's proposal, but it's not the best, we agree.

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11

Hello

 

I did what you say: 2 strokes then leave, then....

 

At home, everything stays clean, even in the drawing!

I'm in 2014, is that the cause????

 

@+

 

Edit: can you do the indicated test and ask us on the post.

 

 

12

I just tried it and I don't have the problem (it's facetized, but not as much)

 

What is the largest size on your part? (wouldn't SW limit the facetization to avoid calculating on large dimensions)

 

Why use a spline? Select Chain/ Insertion/Surface/Extrusion on x mm works directly

(or I missed something)

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13

With the fillet tool you have a better deflection resolution

I go to 0.04604 and I'm not in the red

The image resolution at the max

and the level of detail at most 

@+ ...............

14

Well, I'm losing my Latin: I redid the test I proposed to you and it doesn't facetize.

 

But for my example at the beginning, it's always the same! :/  Note that when I remove the spline to extrude the base segments it doesn't look facetized anymore!. But I really need the spline for my movements (unless I use a method like the one proposed by @frédéric, but I like to understand what's going on for the next time!)!

 

I enclose the play and its drawing.

 

@Pascal, you didn't miss anything, I come to make a surface on a spline to be able to place a constraint between a point of a subset on this surface. It's for a cutscene.


blf_epure.zip
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15

Hello

 

A weird solution but it works on your file, switch the view to shaded more edge...

See attached image!

 


ombre_plus_arete.jpg
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16

Indeed @coyote!

 

The problem is that on a drawing of an assembly containing this part, I have to switch the whole view to Ombre! I can't just pass the part that causes me problems. And that bothers me (yes I know, never happy!).

 

But the lead is interesting! There must be a subtlety that escapes us!

17

Hello

 

It looks like a bug, it's reported on the knowledge base and this one is not fixed (Open status)

 

"File specific: fillet causes extra lines to display in high quality, hidden lines removed/visible (HLR/HLV) drawing view of part"

 

https://customerportal.solidworks.com/eservice_enu/start.swe?SWECmd=InvokeMethod&SWEMethod=GotoRecord&SWEService=SWGotoRecord&ViewName=SW+All+Defects+List+customerportal+-+Search&BusObject=Product+Defect&BusComp=Product+Defect&Id=1-199L2CT&SRN=

 

There are others by searching for "fillet drawing display".

18

Hello

 

Another solution is to convert the view to a sketch (if you're in 2014)!

 

@+

 

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19

@coyote

I'm under 2013. Lost ;)

 

What escapes me is that it's not repeatable.

20

This is clearly stated in the SolidWorks bug:

 

"File specific: fillet causes extra lines to display in high quality, hidden lines removed/visible (HLR/HLV) drawing view of part"

 

 

"Specific to certain files: a fillet displays additional  lines in high quality, hidden lines visible or removed on the part drawing".

 

No solution at the moment.