Hello
In our assemblies we do not use the toolbox (a well-thought-out choice). In the drawings, if we make a cut on the screws, it is automatically cut.
We are forced to exclude it from al cutting manually to avoid this. Is there a trick to set up in the basic file of our screws so that it is perceived as such and so that it is not cut off in the drawings ?
Thank you
@Thierry K.
In my humble opinion NO
either you remove your screws or you make your cut elsewhere
@+
@gt22 and @Thierry K : There is the custom property, aptly named, "IsFastener" which, when it is set to 1, allows you to automatically exclude the said part from the cut (see the "exclude fasteners" checkbox).
Hello
I had this problem, at the time too!
Just click on the section view in the layout and go to the scope of the view it seems to me in the properties of the section view,
All you have to do is click on the screws you don't want to cut.
I hope I have answered your problem and wish you a good day,
MOURET Jordan
@stefbeno It works perfectly, thank you very much.
@jordan.mouret.pro this is the solution we are currently applying, but it's cumbersome, with the IsFastener custom property, it's much better with a significant time saving on future designs.