Operate a step of a numerical control

Out of category
1

Hello 

I know that I am tackling very complicated the. 

But here I would like to make a drawing of a step out of the numerical control of the machine tool, what matters most to me is the visual that when I import my step there is a lot of imported surface (it's not a problem for the drawing) the problem is that there is edges everywhere and visible on the drawing, and when I try to hide them the edges turn blue.

As you can see, I just wish the lines circled in blue weren't visible. 

Have you ever experienced this kind of thing? Feasible or not? 

Thank you for your help


capture.png
2

Hello

If you right-click on the edges and hide/show, does it work?

Yours sincerely.

Mathieu N.


cacher_monter.jpg
3

The edges in blue are those of the surfaces (you may have surfaces that duplicate the volume), in which case these are the surfaces that need to be hidden/removed.

Have you tried to hide tangent edges (right-click on the view/tangent edge)?

4

Hello 

I've already tried, I attach the image when I insert the view before touching it. 

If I try anything, the edges turn blue and for tangent edges, it only removes a few.

So when you look at the room it's just surfaces in fact, there is no volume.

 


capture.png
5

Hello @Haderack 

Try to sew the surfaces that bother you

if it's possible

or better transformed your step into a volume part

or via import

or Via the appropriate tools

@+

3 Likes
6

Indeed, the @gt22 solution seems to be the most suitable.
Can you share your step file?

1 Like
7

here is 


test_simulation7032.stp
8

 @Haderack

Does your file look empty?

no that's it but surprisingly it's super slow don't understand well 

the file seems very rotten ;-)

@+ 

9

Maybe like that? 


test_simulation.step
10

 @Haderack

Have you tried to create a volume via the import options?

@+

11

@gt22

Here are my import options, it only create imported surfaces, I tried to sew the surfaces some work others not. But if not, too bad I'll try to redo the model in volume by starting from scratch. It's just that we have trouble reaching a 3D that looks like the finished part for our workshop.


capture.png
12

 @Haderack

your import options are good, it's simply your step file that's rotten

you can't try to have another format + adequate for SW 

among other things parasolid it's the same core as SW

Where does your file come from?

@+

 

1 Like
13

Hello

your file has a lot of "waste" surface (159 to be exact), only one of the surfaces represents 99% of the geometry of your part,
To do a 1st cleaning easily, you can hide the "right surface" then make a large selection window and remove all the little shit.
Once done you can try an import diagnosis on the right surface, it solves a lot of sewing problems,
then I just have to finish the "details" by hand, (I'm there)

the rest after the soup...

2 Likes
14

I'm going to try Pierre S 

Thank you 

The step comes from a programming software for a rollomatic machine

15

How did you manage to see the surface which represents 99% of the geometry? 


capture.png
16

Hello @Haderack,

To make sure that as much surface as possible is joined from the beginning, I used the "Try to form a volume" option in the import settings.
On the other hand I was a little too optimistic about the "details" because the very faceted area at the end of the cutter has micro surfaces and rather crappy tops,
I'm doing another try in a different way to see,


import_avec_couture.jpg
17

I spent a little time on your file,
Finally the right technique was to import the seamless parts from the surfaces,
 1- Import with no sewing option
2- Sort out the surfaces to be kept (hide them)
3- delete (destroy) all small "parasitic" surfaces (make a large selection window + delete)
4- remove (deactivate) the two faceted surfaces so that we don't bother
5- Make an import diagnosis on the remaining surfaces, crossing your fingers that it works
6- DIY to reconstruct the edges.

I attach the "repaired" file in SW2020 + a X_T

To answer the question at the beginning, yes it is doable but you have to be patient and cunning,


test_simulation7032_31-_.x_t
2 Likes
18

and the SW


test_simulation7032_31.sldprt
19

Hello 

Thank you in advance for devoting your time to my problems, 

Do you know why I can't download your parasolid? When I click on the link I get a page full of code, and your solidworks I can't open it because it's a newer version than mine, I'm still in 2020

Kind regards

20

Attached is a Zip


test_simulation7032_31-_.zip