Macro set up to retrieve the value of a note

Macro
1

Hello
I have a plan with several pages that have the same background.
In this background map I have a note where we assign a value manually, different for each page.

In my macro I would like to retrieve the value of this note for each page in order to use it for the page name (I already have the macro to manage the page name). I don't know how to be able to retrieve this value on each page...

thank you in advance
Cédric

2

Hello

If the note is not linked to any file property but is part of the baseplane template, the ID of the note object must be retrieved in order to process the actions of the note.

1 Like
3

Hello;

To join @Cyril_f in his reasoning, it would be much simpler if these notes were directly derived from a property of the component being planed.
In this way they will be automatically updated in the sheets, or usable via a macro (which becomes less necessary).

4

I was with my head under water... Thank you for your answers
It's not possible to link the note to a property of the part, it's an info that you fill in manually in the drawing

On the other hand, I'm interested in knowing how to retrieve the ID of the note object

5

Hello

You have to loop over all the notes and retrieve the content of the note to find its number and then write a line like this:

if swNote.GetName = "Objet de détailxxx" then ...

For the loop, you have to do something like this:

    Set swView = swDraw.GetFirstView
    Set swNote = swView.GetFirstNote
    Do While Not swNote Is Nothing
    If swNote.GetText = "xxx" then debug.print swNote.GetName: stop
Set swNote = swNote.GetNext
Set swView = swView.GetNext
3 Likes
6

thank you I'll test it!

7

Here I managed to get what I wanted after several attempts!
Here is my complete macro, adapted to our needs: we rename each sheet with the sheet number, and the position number (which can be found in the note). If no note or text in the note is found, then the name of the sheet is not changed

Option Explicit


Sub main()

    Dim swApp As SldWorks.SldWorks
    Dim swModel As SldWorks.ModelDoc2
    Dim swDraw As SldWorks.DrawingDoc
    Dim swSheet As SldWorks.Sheet
    Dim vSheetNames As Variant
    Dim swView As SldWorks.View
    Dim swNote As SldWorks.Note
    Dim i As Long
    Dim pos, feuilleorigin As Long
    Dim FName As Variant
    Dim namesArray As Variant
    Dim noteFound As Boolean

    Set swApp = CreateObject("SldWorks.Application")
    Set swModel = swApp.ActiveDoc
    Set swDraw = swModel

    ' Désactiver l'affichage pour accélérer la macro (mode en arrière-plan)
    swApp.Visible = False

    ' get the list of sheets names
    vSheetNames = swDraw.GetSheetNames
    
    ReDim namesArray(0)
    For i = 0 To UBound(vSheetNames)
        ' increase the array length and add the sheet name to the list
        ReDim Preserve namesArray(UBound(namesArray) + 1) ' increase the array length to put the next value
        namesArray(i) = vSheetNames(i)
        ' temporary rename the sheet to avoid duplicate names (if duplicate, you can not rename)
        Set swSheet = swDraw.Sheet(vSheetNames(i))
        swSheet.SetName (i)
    Next i
    
    ' get the list of sheets names
    vSheetNames = swDraw.GetSheetNames
    For i = 0 To UBound(vSheetNames)
        ' get the original name of the sheet
        FName = namesArray(i)

        ' rename the sheet with the new number and the original part of the name
        Set swSheet = swDraw.Sheet(vSheetNames(i))
        ' activate the sheet to get the current note text
        swDraw.ActivateSheet (vSheetNames(i))
        Set swView = swDraw.GetFirstView ' This is the drawing template

        Set swNote = swView.GetFirstNote
        noteFound = False
        Do While Not swNote Is Nothing
'Debug.Print swNote.GetName
            ' Objet de détail15 = nom de la note qui contient la position
            ' check if the note exists and if it has some text, else do not change the sheet name
            If swNote.GetName = "Objet de détail15" And Trim(swNote.GetText) <> "" Then
                noteFound = True
                Exit Do
            End If
            Set swNote = swNote.GetNext
        Loop
        'swSheet.SetName (i + 1 & Mid(FName, pos))
        If noteFound = True Then
            swSheet.SetName (i + 1 & "-pos" & swNote.GetText)
        Else
            swSheet.SetName (FName)
        End If
    Next i
    
     ' Réactiver l'affichage pour SolidWorks
    swApp.Visible = True
    
    MsgBox "Renumérotation terminée"

End Sub
3 Likes