Let me introduce myself Lucas, I am 24 years old, I work in a design office in the Pas-de-Calais.
Quick question to the community, how do I freeze a view or lock a view in a solidworks drawing ? I don't want my plan or view to update automatically. So I already tried to uncheck "Automatic update of the view" but each time I reopen the plan it resets automatically, and the 2nd solution "Option - System options - Drawing - Performance - Allow automatic updates... " but not very practical since it's an internal parameter to solidworks (so the following plans won't update) and internal to our machine, if a colleague opens my plan on his computer he won't have the same settings as me and therefore the plan will update automatically.
Is it possible to isolate, freeze, or lock a view in a soliworks drawing? (As on CATIA V5)
One solution would be to right-click on the view and select "Convert to Sketch"
It all depends on the purpose of the manoeuvre. You can also save as a pdf or leave the source model and create compositions to take away with each modification.
As of SW2019 , there is a new option to exclude certain views from automatic updating. This option is saved with the file and therefore remembered from one session to the next. Views that are excluded in this way do not update when the model is changed.
Thank you for your answers, I'm working on SOLIDWORKS 2017 and the only alternative I've found is indeed "convert to sketch" but once the manip is done, it's impossible to go back. Too bad they only developed it in 2019... On CATIA V5 you could lock each view without any problem, on solidworks it's much less convenient.
If someone has another solution I'm interested or even remove the link between the plan and the 3D is it possible?
Have a good day to you
Kind regards
[Ps: Freezing view doesn't work, I've already tried it and I don't even know what this function is for. You can manipulate your view as you want and it always updates automatically]
I've never used it but you can create detached drawings, which don't update when modifying the 3D, maybe some here will have more explanations on how they work.
In the MEP in the view palette by clicking on the two arrows that turn in circles in red as long as you don't click on them.
But the second method is to be tested.
In the MEP file, you have to right-click in the future manager on the first line of the tree and uncheck the auto update. As this is a feature saved with the file, it should work even if you reload the same file 20 times.
Also you have to go here and make the modifications and forbid to allow but be careful when you want to do the update anyway you have to force the system
To update automatically when drawings are opened:
Click Tools > Options > System Options > Drawings.
Select Allow automatic updates when opening drawings.
So I've already tried everything. Except for the detached drawing that I just tested, it's not bad just for opening the Plan, without opening (loading) the 3D to avoid it updating automatically.
[The solution:
Click Tools > Options > System Options > Drawings.
Select Allow automatic updates when opening drawings.]
I had already tried this solution which is pretty good, only big disadvantage is that it impacts the SOLIDWORKS parameters so it impacts all the plans, which will not update in auto.. For me it's just for 3-4 shots, I want it to be locked, fixed or more related to the 3D.
In short, the option I want appears in the 2019 version apparently
The 2 best solutions for now :
"convert to sketch" but impossible to go back.
System Options> Drawings > Performance (SDW 2017) > Uncheck "Allow automatic updates when opened.... ". But it's an internal parameter of SOLIDWORKS so it will impact on all levels.
(( You position your block outside the view so that it is not the view as a parent. ))
I use it when I want to show more perspective views than SW allows. It's also very useful for showing a detail when there's potential ambiguity about a part of the piece.
Thank you d.roger for this solution, for my part it's the best for the moment and it suits me very well, I hadn't thought about it. Despite the fact that it's a hack for me, it's enough for me and at least I can go back.
Kind regards
Have a good weekend and have a good weekend everyone:)