Hi all
Does anyone know if we can modify this table:
In fact, I would like the " Description " property to be equal to the name of the item in the welded parts list:
It is created with basic values, it must exist somewhere...
It's a bit tedious to modify everything with a mano, sometimes I have a lot of elements...
Thank you in advance
Hello
To be able to modify the table as it is presented, you must uncheck the link in the right column.
On the other hand, in the document properties, section Welded Constructions - Description of Sheet Metal Bodies, "Use default description" must be unchecked to avoid taking the name "Sheet metal" by default.
Hello
Uncheck the link box I knew (bad screenshot...).
What I would like is for the value of "Description" to be equal to the SW-CutListItemName property, just as "MATERIAL" is equal to SW-Material by default when creating a part in welded construction/sheet metal.
Unchecking this box allows me to give another default name but not a link to a property.
I feel like I'm going around in circles 
.
It is possible to rename the welded parts list folders with the value of the description property (option in the document properties, section Welded constructions always), but not the other way around.
A workaround would be to use the welded parts list IDs.
Well no, actually, my workaround doesn't really work... It's weirdly fucked up.
Hello;
One track per macro:
" This VBA macro allows renaming all cut list features for the weld and sheet metal part based on the name template which can include file and cut list custom property values, file name, configuration name, and free text."
Kind regards.
I understand @a.eriaud , I also went around in circles... So I wrote a suggestion for improvement (since it's the right time to do it... 
)
https://r1132100503382-eu1-3dswym.3dexperience.3ds.com/#community:YxU3ReG0QkqGc0lvBHo6TQ/idea:Spc3ZjEWTK6HaDmAldynXA
Good idea the suggestion for improvement @Silver_Surfer .
On the other hand, it seems to me that it is no longer possible to "vote" for the requests that seem relevant to us? (It was possible before... too bad).
Good initiative @Silver_Surfer , it may lead to something... (if it's a plus looked at than the crash 
report).
I still find it crazy not to be able to modify a table present in the system, you can create all kinds of models (part, assembly, MEP, bill of materials...), you can set up a lot of things but here: nothing!
I wanted to use this option to make detailed bills of materials in MEPs for the assembly of parts in welded construction:
Only the " description " property is accessible and does the job, hence my initial question...
Hello
Which version of SW?
On the 2022 I have this in the options:
And it has the effect of putting this in front of the property:
But it's the association you showed in the second image that you want to make?
To do this, you have to select the last one from the " Welded parts list item name" drop-down list
The handling is to be done for each item...
And if you want, you can create a Designation property to put another name and display the 2 in the table.
OK, maybe I expressed myself badly...
1 - in the MEP nomenclature, there is no " Name of the welded parts list item"
There are a lot of things from the welded construction but not the names of the elements!!
2 - there is " description " which is empty (the nomenclature box is empty)
3 - There is a " description " in the properties of the welded parts list
4 - 
idea! I copy " name of the element..." in " description " and presto.
5 - and in fact, flop. You have to do it for each file and each element, too long...
So after reading your answers, another option (question), can we put in a MEP nomenclature table the variable "Name of the element..."?
Yes:
Be careful, unless I'm mistaken, SW manages the case for the pre-configured fields of its lists.
So "DESCRIPTION" to use and not "Description"
Yes, if: insert->tables->List of welded parts in a multi-part MEP.
I master this part quite well.
No, if: insertion->tables->BOM in a MEP of a multi-body part assembly.
This is where I get stuck, SW does not manage data for MEP in the same way at all if you start from an assembly or a part.
You looked at the custom properties of the welded parts.
In the case below, the body description is linked to the name of the inserted part config
Maybe there are things to do?
It is feasible in an assembly BOM to select " part only " and then " detailed welded part list".
In this case, the description column is linked to the property of the welded parts list of the multi-body part.
On the other hand, you have to modify the Part Number property if you have one.
Then you right-click on the table and save it as a BOM template so that next time all the parameters are already good.
I used the property editor to make a form.
That way it's automatic and always the same.
This is what I do, and I think you are looking for the same thing as me.
I fill in by hand, the names of the articles of the welded parts.
I just put a letter A, B, C... etc
I put this formula in the form
the first one calls me the file name and the second one the name of my welded part
$PRP:" SW-File Name "" SW-CutListItemName "
Example, my file name is 0002
the name of my welded body is A
So after switching the custom property array to automatic
I get 0002A by not forgetting to press apply
And when you modify or make an an an go pack, it regenerates automatically
