Cross-section view with two configurations in SolidWorks

2D plans Layout
1

Hello everyone,
On a drawing, I would like to create a section view showing two configurations simultaneously.
For a classic view (front, top, etc.), no problem: I use the "View from another position" function.

However, when I create a section view from this view, only one of the two configurations appears. I can't find a way to display the second configuration as transparency or overlay in the section view.

Do you have a solution or method to achieve this?
Thank you very much for your help.
Julia

2

Hello,

It's a software limitation so not possible natively (under 2020 anyway).

You can possibly superimpose and align 2 cross-sectional views (it may be boring). You will also have to manually put a font on one of the 2 views.

4 Likes
3

In the same way as @froussel
On the other hand, I will create a model in the assembly in envelope mode that you can hide or show as you wish by clicking on the view or to allow the visibility of this envelope assembly.
But I have a doubt about the possibility of showing the envelope in a section: thinking:, to be tested. But if it doesn't work a model in the desired configuration, insert and exclude from the nomenclature.

1 Like
4

OK, thank you so much for watching.
It's a shame to have a function that seems unfinished... :confused:

5

It may be related to the rules of industrial designs: what type of lines do you put for the second position in section???

2 Likes
6

As @froussel says, drawing rules are the normal rule that limits certain possibilities.
Have you tried envelope mode?

In the main view below, in the view property, it is possible to check the box

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Then in the cup the box is checked
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In your 3D you insert the part in the desired configuration and in the selected part property envelope

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The part changes visual property and an envelope appears in the tree

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The method works for me

  1. The main room
    2) the envelope coin appears in a different font

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And if you don't like the stroke style, you can change it in the document options

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Or directly from the tree structure, with the possibility of changing the color via a layer

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7

Hello;
@FRED78 , why not use the " View from another position " option rather than torment envelopes and fonts?
it would be simpler right? Especially if the configuration already exists...
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This does not work for section views but it is possible to overlay two views together with the alignment options:
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8

Hello,
otherwise (it's not good... but) the view from another position works with a local cut

9

Hello @Maclane
It seems to me that you can do one alignment per frame and not two. And it's not martyred as long as the 3D is the reflection of the drawing. When you superimpose, it's a hack. When you have no choice, why not.
Personally I work with assemblies dedicated to drawing, I don't do this kind of assembly in a study assembly.
And there was a cross-sectional view.

10

@Theo_B we are talking about a cut, a local cut is a normal view. Indeed in this case it works

But another solution that I find hacked ++++
It's making a cut, removing it, but keeping the cut line.
Install a view in place of the cut and make a local cut over the entire view. But here again the cut does not live.

Is this surely the solution you proposed @Theo_B ?

11

yes that was it