When creating a drawing, I used to use 3D dimensions with Creo (tolerances directly included in it, better stability of the system etc etc).
I did find the "model objects" function in Solidworks. It works pretty well overall... except to call the dimension of a datum plane. Try as I might, I can't get it. Well, it's not quite accurate, when I do "whole model", I have the dimension that appears. Unfortunately (and this is the purpose of this option I am well aware), all the dimensions of the model appear. It's not the most practical to find your way around
But suddenly, by going through "selected function", nothing to do, I can't see it on the screen. My dimension is ticked in "marked for drawing"
Hello Coin37coin, Well, that's exactly how we do the 3D dimensioning. But it may be that there are sides that do not come or do not appear. So here's how I make see screenshot =>
Or also when you take over a plan, it may be that they are hidden, usually you are warned that this dimension or dimensions are hidden, just as when you insert the 3D dimension, you also have a small message that tells you so.
All this is with the SW2022 SP4 version.
Good luck. Keep me informed just in case!! … @+. AR.
I must be doing it wrong, I still can't do it. I started by selecting the function in the tree of the corresponding view. I selected everything well like you ... and nothing! I can't find the option you indicate to see the hidden dimensions and annotations. Maybe my 2021 SP4 version doesn't allow it (?)EDIT : J'ai trouvé, une option de la personnalisation de la barre d'outil qui n'était pas cochée
If I make the entire model, I end up with a plethora of dimensions that I don't want to have right away
Sometimes SW doesn't like to insert the dimensions on the sectional views. Or the positioning dimension is on another view. Did you try adding the same nn cut view to see if your dimension in relation to the plan appears?
Indeed, if this is in relation to a plane, and your cut is not in the right plane, it will not come. If it's just for a rating, add it by hand. Good luck. @+. AR.
Hello; What happens if, in the "Model Objects", instead of choosing "Entire Model" as the source, you choose "Selected Function" instead? This should limit the dimensions imported (it all depends on your 3D design mode).
Otherwise, but I don't find this function ineffective, it is possible (in your sketches) to deselect some dimensions to export in your Drawing. Of course I forgot the name of this function but it is accessible by right-clicking on the dimensions (I think it's about "declare this dimension for the Layout" or something similar.
Well, is it possible, if I understand correctly, to have the 3D model at best if it is not confidential, or else take screenshots of your 3D part detailing each step of the realization of your part, i.e. each function with the dimensioning as previously done on your MEP.
Otherwise you always go to your creation tree, you go to the function where you want to have this dimension and you insert it manually and that's it, it should come in your desired view of MEP, but will not be editable.
Thank you all for your answers and your brainstorming.
I'm going to try to forget no one in my answers.
@Maclane, nothing happens precisely when I choose " selected function". That's why I come to use " object of the template "... but too many dimensions that are displayed and without the possibility to select some of them (a Creo point that I miss that)
@A.A, what do you call manually inserting the dimension from the creation tree? I'm not against detailing each step of the realization of my piece ... but it's going to be very long! (67 functions) That said, if it's to come up with this famous plan, luck: it's my second job. So I did an extrusion of one Ø and then placed the plane at a certain distance
@opiep27, yes, I have the same problem with a very simple test part. As a result, (to go in the direction of @a.r. I enclose it to you in copy Whatever the view, this dimension does not want to appear in " selected function" mode test. SLDPRT (57.0 KB)
The problem is that this function in the sense of function for drawings does not exist. The function ends on a plan and therefore does not have a dimension to display. So I don't really see a solution except to uncheck all the dimensions that you don't want to appear in the plan and thus use the entire model.
So I wanted to say, when you go into your 3D model, you go to the function where you want to have this dimension, you simply put it in the sketch of the function where you want to have this dimension.
To answer your question, which I'm going to answer not a question, why use a plan to make an extrusion?
I would simply do this cylindrical extrusion at the desired dimension, and then the desired material removal. And so all your rating will be put in your plan.
On SW2020 using a plane and an extrusion until this plane no worries the dimension of 53.3, fits well with the objects of the model and the option marked for the drawing. SW2020 file attached. Part3.SLDDRW (118.2 KB) Item3.SLDPRT (51.7 KB)
@sabadenis : I also just tested, the dimension is only inserted if you choose "whole model" in the import of the model's objects. But do you manage to import this dimension with just import "selected function"? I didn't succeed under SW2020
More prosaically, because I'm used to thinking that way. There, you can't see it on the test part, but I have a few other functions that use this plan afterwards (among other things for drafts) In addition, I like to have a reference and identified plane to move rather than looking for the initial function hoping not to have messed up. And the icing on the cake, I can remove an extrusion without losing my hook plane for the other functions
